opSweep multiple edges

tonvis

https://cad.onshape.com/documents/e962c03684a97b9568b92c37/w/dd893095a99b64b5e8c7e121/e/5c53b3c17735e317d52b0a55

Can somebody please help me out, I tryed everything to obtain a full path along a set of edges.

line 373

            /*  ----------------------  Why does this not generate multiple edges

               opSweep(context, id + "sweep4", {
               "profiles" : sketchEntityQuery(id + "sketch8", EntityType.EDGE, "flat"),
               "path" : qCreatedBy(id + "sketch7", qEverything(EntityType.EDGE))

               });
             */

Many thanks for any support.

Jake_Rosenfeld

Hi @tonvis

First issue:

qCreatedBy(id + "sketch7", qEverything(EntityType.EDGE))

is not a valid query, I think what you are trying to say might be:

qCreatedBy(id + "sketch7", EntityType.EDGE)

but by adding the following line of code, I can see what that resolves too:

debug(context, qCreatedBy(id + "sketch7", EntityType.EDGE));

You will need to be more discerning in your query to only capture the edges you want to sweep over.

This seems to get what you want:

            const path = qUnion([
                        qCreatedBy(id + "helix4", EntityType.EDGE),
                        sketchEntityQuery(id + "sketch7", EntityType.EDGE, "arc2"),
                        sketchEntityQuery(id + "sketch7", EntityType.EDGE, "arc1"),
                        sketchEntityQuery(id + "sketch7", EntityType.EDGE, "offset1"),
                        sketchEntityQuery(id + "sketch7", EntityType.EDGE, "offset2")
                    ]);

            opSweep(context, id + "sweep4", {
                        "profiles" : sketchEntityQuery(id + "sketch8", EntityType.EDGE, "flat"),
                        "path" : path
                    });

The "debug" call is very powerful to visually see what a query resolves to.  When I was working out the correct edges to select, I built up all the pieces of the qUnion in a call like this:

            debug(context, qUnion([
                        qCreatedBy(id + "helix4", EntityType.EDGE),
                        sketchEntityQuery(id + "sketch7", EntityType.EDGE, "arc2"),
                        sketchEntityQuery(id + "sketch7", EntityType.EDGE, "arc1"),
                        sketchEntityQuery(id + "sketch7", EntityType.EDGE, "offset1"),
                        sketchEntityQuery(id + "sketch7", EntityType.EDGE, "offset2")
                    ]));

Which showed this nice helpful red highlight:

Then I knew the query was ready to be passed into opSweep!

tonvis

Jake thanks for your help, I will give it a try.

Featurescript is very nice , the scrips are very helpfull for anybody. The only problem  is  lack of examples. I study all I can find in publiced ones.

Greetings  tonvis