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API Sketch Geometry ID

Lucas_CrupiLucas_Crupi Member Posts: 5 EDU
in Community Support
When calling the /partsudios/d/{did}/{wvm}/{wvmid}/e/{eid}/features from the REST API, there are some geometry references in the form of three characters, eg. "geometryIds": ["JMF"]

I have been able to find the ID of edges using /partsudios/d/{did}/{wvm}/{wvmid}/e/{eid}/bodydetails however, when the referenced geometry is an entity within a sketch such as a line, I cannot seem to find the appropriate API call. 

Any help or resources are greatly appreciated.

Best Answer

Answers

  • alan_baljeualan_baljeu Member, User Group Leader Posts: 111 ✭✭
    I believe "entityId"  is what you need.  See fragment below.

      "features" : [ {
        "type" : 151,
        "typeName" : "BTMSketch",
        "message" : {
          "entities" : [ {
            "type" : 4,
            "typeName" : "BTMSketchCurve",
            "message" : {
              "geometry" : {
                "type" : 115,
                "typeName" : "BTCurveGeometryCircle",
                "message" : {
                  "radius" : 0.05423578839196134,
                  "xCenter" : -0.03895397484302521,
                  "yCenter" : -0.03339579701423645,
                  "xDir" : 1.0,
                  "yDir" : 0.0,
                  "clockwise" : false
                }
              },
              "centerId" : "pUzfMw2i2Kly.center",
              "internalIds" : [ ],
              "isConstruction" : false,
              "parameters" : [ ],
              "isFromSplineHandle" : false,
              "entityId" : "pUzfMw2i2Kly",
              "namespace" : "",
              "hasUserCode" : false,
              "nodeId" : "M3H5t/In4rdlnyQ+z"
            }
          }
    Creating knowledge-driven design automation software, for molds, etc.
    www.virtualmold.com

  • alan_baljeualan_baljeu Member, User Group Leader Posts: 111 ✭✭
    I see the problem here: Extrude features reference geometry by geometryIds, and while we can get these ids for bodies, there's no id presented for sketch elements.  So here's a feature definition:

    {
        "type" : 134,
        "typeName" : "BTMFeature",
        "message" : {
          "featureType" : "extrude",
          "featureId" : "FukfxxLNUGr2Ytg_0",
          "name" : "Extrude 1",
          "parameters" : [ {
                  ... 
               {
            "type" : 148,
            "typeName" : "BTMParameterQueryList",
            "message" : {
              "queries" : [ {
                "type" : 138,
                "typeName" : "BTMIndividualQuery",
                "message" : {
                  "geometryIds" : [ "JGC" ],
                  "hasUserCode" : false,
                  "nodeId" : "FhjpxqVvrJ9zlPM"
                }

    and the arc (or face?) JGC is defined in the program by sketch entity "pUzfMw2i2Kly", but there's nowhere in the API to identify this link.
    But if I construct an extrude using a body face as reference, that reference can be found in the bodydetails call.
    Creating knowledge-driven design automation software, for molds, etc.
    www.virtualmold.com

  • alan_baljeualan_baljeu Member, User Group Leader Posts: 111 ✭✭
    Answer ✓
    The documentation has the resolution, thought it's a bit weird:

    Feature List API | Onshape Developer Documentation (onshape-public.github.io)

    We ask Onshape to run a featurescript query, get the geometry ID as a result, and that there is your geometryId.


    Creating knowledge-driven design automation software, for molds, etc.
    www.virtualmold.com

  • alexander_koppelalexander_koppel Member Posts: 5 ✭
    alan_baljeu said:
    The documentation has the resolution, thought it's a bit weird:

    Feature List API | Onshape Developer Documentation (onshape-public.github.io)

    We ask Onshape to run a featurescript query, get the geometry ID as a result, and that there is your geometryId.


    I have tried this method, and it doesn't seem to work. I was able to get the geometryID of a "part of a sketch", but can't get the geometry of the only edge in that sketch. For context, the sketch I am using has featureID:Fd5TnWYq9UpUQe5_0, only consists of a single line, and is named "Revolute Line".


    The script that returned the "part of the sketch": 
    "script":"function(context is Context, queries){return transientQueriesToStrings(evaluateQuery(context, qCreatedBy(makeId('Fd5TnWYq9UpUQe5_0'), EntityType.BODY)));}"

    I know this as I tried to use the returned geometryID as a revolute axis:



    Then I tried specifying, GeometryType.LINE, and got an empty return value, the script:
    "script":"function(context is Context, queries){return transientQueriesToStrings(evaluateQuery(context, qGeometry(qCreatedBy(makeId('Fd5TnWYq9UpUQe5_0'), EntityType.BODY),GeometryType.LINE)));}"

    Which returned:
    {
      "console" : "",
      "notices" : [ ],
      "result" : {
        "type" : 1499,
        "typeName" : "BTFSValueArray",
        "message" : {
          "value" : [ ],
          "typeTag" : ""
        }
      },
      "serializationVersion" : "1.1.23",
      "sourceMicroversion" : "183175352bf8cf2f4fb64556",
      "rejectMicroversionSkew" : false,
      "microversionSkew" : false,
      "libraryVersion" : 1803
    }
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