I have imported a logo, is there a way to resize the complete logo in Onshape.

dirk_van_der_vaart

Now I have resize the logo in a program outside onshape, import it again etc.etc.
The proportion of the logo sould stay intact.
Offset is not an option.
Thanks in adva

philip_thomas

I am assuming that the import is 2D, if not, start after the extrude (step 3);

1) Import logo (2D) as DXF/DWG
2) Insert logo into part studio sketch
3) Extrude logo to form solid body(ies)
4) Use transform-scale to resize logo
5) Apply mate connector to location on logo
6) Apply mate connector to desired target location (presumably on some other part)
7) Use transform-by-mate-connector to position logo

I hope this helps - Philip . . . 

philip_thomas

I am assuming that the import is 2D, if not, start after the extrude (step 3);

1) Import logo (2D) as DXF/DWG
2) Insert logo into part studio sketch
3) Extrude logo to form solid body(ies)
4) Use transform-scale to resize logo
5) Apply mate connector to location on logo
6) Apply mate connector to desired target location (presumably on some other part)
7) Use transform-by-mate-connector to position logo

I hope this helps - Philip . . . 

ben_druce929

@philip_thomas - Editing DXF's in a sketch in Onshape is a nightmare. The workflow that I'd love to see would be similar to whats in SolidWorks:

• Import DXF into sketch
• Group DXF lines into a 'group' or 'block'
• Move, scale, rotate DXF as necessary
• Extrude as needed

glen_dewsbury

On insertion of DXF, the first driving dimension added will set the scale of overall DXF. No further dimensions will have this affect. You'll still need to set location as Philip describes.

martin_kopplow

https://forum.onshape.com/discussion/comment/122322#Comment_122322

That makes an edit after the fact pretty hard to do. I have come to an alternative logo-workflow where I would import it as usual, into it's own part studio, then scale it to something 'round mumber' like say 100 millimeters in width, using the first dimension in the sketch, then fix everything in place. After that, I create surfaces or an extrude from it and apply a scaling factor to the relult by means of the transform feature.I derive that into my design and use projections or booleans, whatever is needed. I can then go back to the transform/scale feature and type a new size at any time without breaking anything, or even make logo size a variable.

jelte_steur814

I usually do it this way:

This way I can import into a new part studio the logo with a proper size in one go.
I'll transform (MC to MC) it into place afterwards.
then boolean it off/on or split face etc. Possibly after a 'replace face' with offset face set for curved faces.

Best to do this in a separate document (perhaps in a logo library folder) so it's easy to find and import into new projects for proper reuse.