Fillet edges only on faces in extruded direction

richard_marcus

Is there a query that will give me only the edges on a body that are in the extruded direction (i.e. perpendicular to the sketch plane)? I don't want to fillet anything on the end faces. Queries are still a little bit of a mystery to me.

This seems to work if I just extruded a body:

var ExtrudedEdges is Query = qSubtraction(qSubtraction(qCreatedBy(id + "extrude1", EntityType.EDGE), qCapEntity(id + "extrude1", true)), qCapEntity(id + "extrude1", false));

opFillet(context, id + "fillet1", {

                "entities" : ExtrudedEdges,

                "radius" : 0.5 * millimeter

        });

However, if I have done other operations (such as boolean remove) on the body, the qCapEntity doesn't really work anymore since it references a feature creation not the body.
Any advice?

konstantin_shiriazdanov

once i needed the same functionality, and i wrote a function

function selectParallelEdges(context is Context, edges is Query, vector is Vector)<br>{<br>    var parallelEdges = [];<br>    for (var edge in evaluateQuery(context, edges))<br>    {<br>        if (parallelVectors(evLine(context, { "edge" : edge }).direction, vector))<br>        {<br>            parallelEdges = append(parallelEdges, edge);<br>        }<br>    }<br>    return qUnion(parallelEdges);<br>}<br><br>

konstantin_shiriazdanov

once i needed the same functionality, and i wrote a function

function selectParallelEdges(context is Context, edges is Query, vector is Vector)<br>{<br>    var parallelEdges = [];<br>    for (var edge in evaluateQuery(context, edges))<br>    {<br>        if (parallelVectors(evLine(context, { "edge" : edge }).direction, vector))<br>        {<br>            parallelEdges = append(parallelEdges, edge);<br>        }<br>    }<br>    return qUnion(parallelEdges);<br>}<br><br>

Jake_Rosenfeld

Seems like you're doing pretty well with queries already!  You could try something like this:

        // Get the cap entities
        var caps = qUnion([qCapEntity(id + "extrude1", true), qCapEntity(id + "extrude1", false)]);
        // Filter for just the faces
        var capFaces = qEntityFilter(caps, EntityType.FACE);
        
        // Do something to the extruded body
        ............

        // Get all the edges on the body created by extrude1
        //    qCreatedBy(id + "extrude1", EntityType.EDGE) will only have the edges
        //    created by the extrude, so we do something more complicated
        var allEdges = qOwnedByBody(qCreatedBy(id + "extrude1", EntityType.BODY), EntityType.EDGE);
        // Get all the edges surrounding the cap faces
        var capEdges = qEdgeAdjacent(capFaces, EntityType.EDGE);
        // Subtract the cap geometry
        var desiredEdges = qSubtraction(allEdges, capEdges);
        
        // run opFillet on the desiredEdges
        opFillet(...);

Let me know if this works for you!

Edit: Nice function Konstantin!

emagdalenaC2i

If you are working with sheet metal parts you can use this in the selection to avoid that edges:

        annotation { "Name" : "Select two parallel edges that belong to the same planar face", "Filter" : (ActiveSheetMetal.NO && EntityType.EDGE && EdgeTopology.TWO_SIDED && GeometryType.LINE

                            || EntityType.EDGE && SheetMetalDefinitionEntityType.VERTEX

                            && ConstructionObject.NO && SketchObject.NO && ModifiableEntityOnly.YES),

                    "AdditionalBoxSelectFilter" : EntityType.EDGE,

You can see an example here https://cad.onshape.com/documents/3d52520839c0fa3587798c0f/w/2c36a47f3c428c7a3f8e3a5f/e/acc8270b7d8719708565ee1e

Just try to create a full round in a sheet metal part

antti_andreimann

Seems like only the first line of Konstantin's answer is visible now. Did something happen to the forum software that it ate the rest of the code?

antti_andreimann

Let's see if some copy-paste brings back the lost code.<br><br>

<code>function selectParallelEdges(context is Context, edges is Query, vector is Vector)<br>{<br>&nbsp;&nbsp;&nbsp; var parallelEdges = [];<br>&nbsp;&nbsp;&nbsp; for (var edge in evaluateQuery(context, edges))<br>&nbsp;&nbsp;&nbsp; {<br>&nbsp;&nbsp;&nbsp;&nbsp;&nbsp;&nbsp;&nbsp; if (parallelVectors(evLine(context, { "edge" : edge }).direction, vector))<br>&nbsp;&nbsp;&nbsp;&nbsp;&nbsp;&nbsp;&nbsp; {<br>&nbsp;&nbsp;&nbsp;&nbsp;&nbsp;&nbsp;&nbsp;&nbsp;&nbsp;&nbsp;&nbsp; parallelEdges = append(parallelEdges, edge);<br>&nbsp;&nbsp;&nbsp;&nbsp;&nbsp;&nbsp;&nbsp; }<br>&nbsp;&nbsp;&nbsp; }<br>&nbsp;&nbsp;&nbsp; return qUnion(parallelEdges);<br>}