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Advanced Part Design Exercise: Vent

jamescbonneyjamescbonney Member Posts: 14 ✭✭
in Learning Center



I am having a problem with step 16 in this exercise. I have followed the instructions for the step, but the result of the feature pattern in my part studio differs from that shown in the example, so I must be missing something.

There is a hint in the sketch step to dimension from the vertical and horizontal construction lines to the radius of the slot rather than the end point of the arc. I have tried changing the vertex selected for the dimension and it did change my result, but I did not get the result shown above. 

Below are screenshots of the sketch, first circular pattern, and the troublesome second circular pattern. 

Here is a link to the document: https://cad.onshape.com/documents/c6d77c61f4665964b85bd18f/w/4c54d3eb1fb2eab39d5f4b28/e/c89354e2446653e5ef20b831

Here is a link to the exercise: https://learn.onshape.com/learn/course/advanced-part-design/advanced-features/exercise-vent?page=2 


Best Answers

  • tim_hess427tim_hess427 Member Posts: 648 ✭✭✭✭
    Answer ✓
    Maybe the highlighted dimension is supposed to be perpendicular to the construction line, but in the messed up model its setting a vertical distance between the center of the arc and the endpoint of the line. 

    Try erasing that dimension and re-doing it, but make sure you select the construction line instead of the end-point on the line?


  • EvanReeseEvanReese Member, Mentor Posts: 2,605 PRO
    Answer ✓
    @tim_hess427 was right. the dimension needed to be between the arc center and the line, not the endpoint of the line.
     
    It feels confusing because the result is the same in this sketch, but the results in the patterned sketches are different. When it's dimensioned to the point, the patterned sketches start to do this because the dimension is still vertical.


    Evan Reese
    The Onsherpa | Reach peak Onshape productivity
    www.theonsherpa.com
  • bruce_williamsbruce_williams Member, Developers Posts: 842 EDU
    Answer ✓
    @jamescbonney

    I was confused on that for a bit also. It is not relevant if you choose arc center or vertex of the slot centerline.  What the others are talking about is the horizontal construction LINE, and not choosing its vertex.

    www.accuratepattern.com

Answers

  • EvanReeseEvanReese Member, Mentor Posts: 2,605 PRO
    I just worked through the exercise, and it worked for me, but I fiddled around with it trying to reproduce your results and couldn't see how. Can you make your document public, not just share a view-only link? Otherwise we can't dig into your features to see how it's set up. In looking at yours though, It could be something with this dimension. It seems to get bigger with each iteration of the sketch in your screenshot, but it should always be 5mm.


    Evan Reese
    The Onsherpa | Reach peak Onshape productivity
    www.theonsherpa.com
  • tim_hess427tim_hess427 Member Posts: 648 ✭✭✭✭
    Answer ✓
    Maybe the highlighted dimension is supposed to be perpendicular to the construction line, but in the messed up model its setting a vertical distance between the center of the arc and the endpoint of the line. 

    Try erasing that dimension and re-doing it, but make sure you select the construction line instead of the end-point on the line?


  • KatieHuffmanKatieHuffman Member, Onshape Employees, Developers Posts: 194 image
    @jamescbonney follow what @tim_hess427 points out. In step 12, when you add the dimensions you have to be careful how you attach the leaders to the sketch geometry as it says in the hint. This is important to get the pattern to update correctly later in the design because depending on how you attach the leaders changes how the variables pattern.
  • jamescbonneyjamescbonney Member Posts: 14 ✭✭
    Thanks for the responses. @Evan_Reese @tim_hess427 @KatieHuffman

    I have made the document public. 

    I will check back to this exercise and see if the suggested solutions resolve the problem. 
  • EvanReeseEvanReese Member, Mentor Posts: 2,605 PRO
    Answer ✓
    @tim_hess427 was right. the dimension needed to be between the arc center and the line, not the endpoint of the line.
     
    It feels confusing because the result is the same in this sketch, but the results in the patterned sketches are different. When it's dimensioned to the point, the patterned sketches start to do this because the dimension is still vertical.


    Evan Reese
    The Onsherpa | Reach peak Onshape productivity
    www.theonsherpa.com
  • jamescbonneyjamescbonney Member Posts: 14 ✭✭
    Thanks @Evan_Reese

    To select the arc center did you hover over the end point of the arc and then move to the center? 
    I right clicked and used the select other option and tried the available options, but apparently I did not have luck selecting arc center. 
  • EvanReeseEvanReese Member, Mentor Posts: 2,605 PRO
    I didn't do anything special there. I just clicked the point then the edge. I highlighted the two things to dimension to.


    Evan Reese
    The Onsherpa | Reach peak Onshape productivity
    www.theonsherpa.com
  • bruce_williamsbruce_williams Member, Developers Posts: 842 EDU
    Answer ✓
    @jamescbonney

    I was confused on that for a bit also. It is not relevant if you choose arc center or vertex of the slot centerline.  What the others are talking about is the horizontal construction LINE, and not choosing its vertex.

    www.accuratepattern.com
  • jamescbonneyjamescbonney Member Posts: 14 ✭✭
    @Evan_Reese @bruce_williams

    Ah! I see now! I misread the clue. 
  • AshdancanAshdancan Member Posts: 4 EDU
    Hello

    I did all procedures but in the second circular pattern, nothing happened.
  • AshdancanAshdancan Member Posts: 4 EDU
    Hello


    I did all procedures but in the second circular pattern, The result was absolutely different. I did all requirements mentioned in the exercise but failed.
  • AshdancanAshdancan Member Posts: 4 EDU
    edited February 2023
    Hello


    I did all procedures but the result was absolutely different. I did all requirements mentioned in the exercise but failed.
     please anyone can help me??. I think I did all correctly.
    Thanks for all
  • AshdancanAshdancan Member Posts: 4 EDU
    Ashdancan said:
    Hello

    I did all procedures but in the second circular pattern, nothing happened.

    Ashdancan said:
    Hello


    I did all procedures but in the second circular pattern, The result was absolutely different. I did all requirements mentioned in the exercise but failed.


  • S1monS1mon Member Posts: 3,650 PRO
    @Ashdancan
    It would be much easier to help you if you can share a public document. These kind of patterns are tricky and little details make a big difference.

    Simon Gatrall | Product Development Specialist | Open For Work

  • obyfolia_dsobyfolia_ds Member Posts: 4 ✭

    I'm facing the same problem, part 16 of the lesson just says to add a bunch of parameters and does not explain why, I can't make sense of it enough to say that I learned how to do it. On top of that I can't make the second pattern to show up.

    I really really enjoy using Onshape, but some it's issues and quirks make me wanna punch my pc.

    Can anyone take a look and tell me what I did wrong. And where can I go to understand how just adding the variables to the features creates and stacked circular array.

    Public document:

    https://cad.onshape.com/documents/c2ab454447157a1d34f9943d/w/f341262c74c4efd974756d98/e/ffe1c39895754f0cefe3d3b9?renderMode=0&uiState=68cb4d3de96fa2d06b6a270b

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