Rotating Sketch Features

stuart_every

Drew a feature in a Sketch, and then needed to change its position on the Component Circumference.

Couldn't figure out how to Rotate these features, nor how to choose a Centre of Rotation.

Ended up using the Transform (I think) function, which gave me the white arrow Tool. I dragged the 'point' of this tool, to the Rotation Centre, then used the Rotate icon to select that function, then inputed the angle; all ok so far...

Then clicked the left button to OK the change, at which point the feature shot across to a random point in the Sketch

What am I doing wrong here?

viru

@stuart_every,Transform adjusts a sketch's location and orientation.Please refer below steps.

Steps

1. Click .
2. Select the sketch entities you want to move.
3. Use the manipulator to drag and orient the sketch.
4. Click in space when the sketch is placed and oriented as desired.

When rotating via the manipulator, an angle field activates. Enter an angle, press Enter, and click in space to set the angle:

Place the manipulator’s ball point to orient a snap point for the sketch:

1. Drag the ball point to a point on the sketch you wish to use as a snap point:

   

2. Use the plane to drag the sketch ball point to the snap point on another sketch (in this case the lower-left point of the square):

   

3. Click off the sketch to set the transform:

   

For more information, see Transforming sketches

Tips

• Pre- and post-selection is supported; entities can be added and removed during the operation.
• Click off the sketch or press Enter to commit the transform and exit the operation. Press Esc to cancel the operation.
• In the case of no rotation or 180 degree rotation, internal constraints are unchanged.
• In the case of 90 degree or 270 degree rotation, horizontal and vertical constraints swap.
• In some cases, construction geometry may be added to maintain degrees of freedom.
• Directed dimensions are deleted, and may be replaced with construction geometry and minimum dimensions.
• Transform is also supported for images, text, DWG, and DXF
  

The Sketch Transform tool now lets you translate and rotate by exact distances or angles and snap to existing sketch geometry.

viru

@stuart_every,Transform adjusts a sketch's location and orientation.Please refer below steps.

Steps

1. Click .
2. Select the sketch entities you want to move.
3. Use the manipulator to drag and orient the sketch.
4. Click in space when the sketch is placed and oriented as desired.

When rotating via the manipulator, an angle field activates. Enter an angle, press Enter, and click in space to set the angle:

Place the manipulator’s ball point to orient a snap point for the sketch:

1. Drag the ball point to a point on the sketch you wish to use as a snap point:

   

2. Use the plane to drag the sketch ball point to the snap point on another sketch (in this case the lower-left point of the square):

   

3. Click off the sketch to set the transform:

   

For more information, see Transforming sketches

Tips

• Pre- and post-selection is supported; entities can be added and removed during the operation.
• Click off the sketch or press Enter to commit the transform and exit the operation. Press Esc to cancel the operation.
• In the case of no rotation or 180 degree rotation, internal constraints are unchanged.
• In the case of 90 degree or 270 degree rotation, horizontal and vertical constraints swap.
• In some cases, construction geometry may be added to maintain degrees of freedom.
• Directed dimensions are deleted, and may be replaced with construction geometry and minimum dimensions.
• Transform is also supported for images, text, DWG, and DXF
  

The Sketch Transform tool now lets you translate and rotate by exact distances or angles and snap to existing sketch geometry.

shade_wilson

How do you rotate a sketch in 3D? For example, if you were facing the object in the same direction the entire time and then rotating it exactly 90 degrees, it would look completely flat, just like turning around a piece of paper. I cannot figure out how to do this.

NeilCooke

shade_wilson said:

How do you rotate a sketch in 3D? For example, if you were facing the object in the same direction the entire time and then rotating it exactly 90 degrees, it would look completely flat, just like turning around a piece of paper. I cannot figure out how to do this.

Edit the sketch plane in the sketch dialog to point to a plane at 90 degrees

robert_stiles

@NeilCooke what if you create a sketch, you need it initially where you have created it, but then you also need the same sketch, rotated 90 degrees in its x or y axis later downstream ? 
I can't re-set its plane, because I need it where it is initially
I can't projects any content because its 90 degrees rotated...
do I have to create a further sketch @ 45 degrees and double project around the corner? Seems a bit heavy. The transform feature can't pick sketches unless I'm missing something?
Any other workflows? 
Thanks
Rob

NeilCooke

@robert_stiles you would have to create a new sketch and paste the entities into it, although they would not be linked. Alternatively, if the sketch is closed, you could create a zero offset surface on the sketch face, then transform the surface then use that for extrude etc.

robert_stiles

@NeilCooke, thankyou so much for the reply. 
The second option will work for me, thanks. 
It would be good if you could apply the transform feature to sketches though ! 

eric_pesty

Another option would be to do a circular pattern on the sketch feature (if all you need is a 90deg "offset").
One more alternative is to use the "transform pattern" custom feature (if a simple circular pattern doesn't give you enough control) which does allow transforming a sketch (similar to the zero offset surface) to save a step.

NeilCooke

Also, if it is an extrude you're creating, rather than transform the sketch, create the first extrude as a new part, transform/copy, then merge both into the main part.

robert_stiles

Ah @eric_pesty... pattern a feature - of course. I should have known that. (there no face-plant emoji ? now there's a valid Improvement request if ever I came up with one)
Thanks everyone. Very speedy responses.